Skip to content

PCB and Box

When building high-end audio hardware, the enclosure dictates not just the aesthetics of the pedal, but the entire mechanical strategy of the KiCad PCB layout. The industry standards are based on die-cast aluminum boxes originally standardized by Hammond Manufacturing. Here is a breakdown of the two most common footprints for a project of this scope:

The 1590BB (The Wide Format)

  • Dimensions: Roughly 4.7" x 3.7" x 1.3" (119 x 94 x 34mm).
  • The Vibe: Wider and slightly shallower. It’s the classic choice for dual-footswitch pedals or designs that require a lot of panel controls.
  • Why it works for Bloodhoney: If Audio Innovations is aiming for a larger, more imposing visual footprint, or if the plan eventually includes adding a second footswitch (perhaps a dedicated bypass and a secondary function switch), this is the canvas for it.
  • Layout: Maximum real estate is available. The three pots can be spaced out widely for easy tweaking without bumping other knobs. However, the slightly shallower depth means designers must be mathematically precise about how the Daisy Seed and unity-gain buffers stack up against the internal height limits.

The 125B (The Modern Boutique Standard)

  • Dimensions: Roughly 4.7" x 2.6" x 1.5" (122 x 66 x 39mm).
  • The Vibe: This is the current go-to for premium, single-footswitch pedals. It is deeper than vintage enclosures.
  • Why it works for Bloodhoney: The extra depth is incredibly forgiving when stacking components. Since the design utilizes a Daisy Seed, vertical clearance is required for it to sit on its headers above the main board. The 125B easily accommodates this, and the depth allows for top-mounted audio and power jacks, which saves precious pedalboard space.
  • Layout: With three pots (Mix, Threshold, Focus), they can easily be arranged in a triangle or a straight horizontal line across the top half of the faceplate.
  • Finishing: Platforms like Tayda Electronics offer the 125B in massive varieties of powder-coated finishes (e.g., metallic sand textures, hammer finishes) which is great for scaling boutique pedals without having to paint them in-house.

The 125B is an excellent choice. It perfectly fits the modern boutique aesthetic for Audio Innovations, and the extra depth will be a lifesaver when stacking the Daisy Seed over the main board.

The Layout Strategy

Since a narrower footprint is being used, managing vertical real estate is key. Here is how the schematic translates into a 125B layout strategy.

PCB Dimension Limits for the 125B

  • Max PCB Sizing: To safely clear the corner screw posts and internal side walls, the absolute maximum PCB size should be roughly 58mm wide by 72mm long (2.25" x 2.85").
  • Vertical Height Constraint: There is about 30mm (1.2") of internal vertical clearance once the lid is on. Since the Daisy Seed sits on female headers, one must calculate the combined height of the main PCB, the headers, the Daisy Seed itself, and any electrolytic caps to ensure the backplate closes flush.

  • Mechanical Placement & Drilling:

    • The Top-Mounted Jack Advantage: The 1.57" height of the 125B is exactly what allows for top-mounted audio and DC jacks. A standard practice is to mount the DC jack right in the top-center, with the 1/4" mono Input and Output jacks flanking it on either side.
    • Board-Mounted Hardware: To avoid a rat's nest of off-board wiring, a PCB layout should be utilized that solders the potentiometers, toggle switches, and I/O jacks directly to the board. The mechanical nuts on the outside of the enclosure will hold the entire PCB assembly in place—no standoffs required.
    • Drill Templates: Because top-mounted 125B layouts are so dense at the top edge, precision is critical. It is highly recommended to use a center punch and a 1:1 scale paper template (often drafted in KiCad or Sketchup), or a physical metal drill template like those from PedalPCB.

Because the noise floor must be carefully managed with those single 0.1µF bypass caps and separating the digital Daisy Seed from the analog I/O buffers, the physical layout is the first line of defense. A standard approach is to mount the pots and jacks directly to the PCB. The PCB is then secured to the enclosure by the nuts of those pots and jacks, requiring zero standoffs or screws.

Board Outline (Edge.Cuts)

The internal dimensions of a standard 125B are roughly 118mm x 62mm (accounting for the screw posts in the corners), but to ensure a drop-in fit with zero mechanical stress, the maximum working PCB area should be restricted to 58mm x 72mm (2.25" x 2.85").

When drawing the board outline in KiCad's Edge.Cuts layer, following these parameters ensures the board sits flush:

  • The Primary Rectangle: A bounding box measuring 58mm wide and 72mm tall should be drawn.
  • Corner Relief (Crucial): A perfect 90-degree corner on a 58x72mm board will collide with the 125B's internal screw posts. The corners must be relieved. A 3mm chamfer (a 45-degree angle cut) or a 3.5mm corner radius should be added to all four corners of the outline.
  • Origin Placement: For a smoother workflow when aligning top-mounted hardware, the drill/place origin (0,0) should be set to the top-center of the board outline. This makes aligning the top-mounted DC jack, Input, and Output jacks perfectly symmetrical across the X-axis.
  • Clearance Check: Sticking strictly to this 58x72mm boundary ensures that the PCB assembly can be tilted and maneuvered into the enclosure past the bottom lip. It leaves just enough room below the board for the 3PDT footswitch wiring, while keeping the vertically oriented Daisy Seed and the OPA2134 unity-gain buffers safely away from the metal sidewalls.

Mechanical Placement Strategy

Because the 125B is deep, it provides the clearance for top-mounted jacks, which are highly preferred on modern pedalboards.

  • The Jacks (J1, J2, and Power): Placed at the very top edge of the board.
  • The Pots (RV1, RV2, RV3): The Mix, Threshold, and Focus pots can be arranged in an inverted triangle or a straight horizontal line just below the jacks.
  • The Daisy Seed (U1): Because the 125B is narrow, the Seed will likely need to be oriented vertically, running down the center or slightly offset to one side.
  • The Analog Section (U1A/B): To minimize noise, the OPA2134 unity-gain buffers and those specific 0.1µF bypass caps should be placed as far from the Daisy Seed's digital clock lines as possible—likely clustered near the bottom of the board closer to the footswitch location.

Assigning Footprints

Before moving to the PCB editor and drawing the board outline, KiCad needs the exact physical dimensions for the parts. The mechanical components (things that stick out of the box) dictate where everything else goes.

Here are the recommended standard KiCad footprints (or custom pedal library equivalents) for the hardware used in this build:

  • The Microcontroller (Daisy Seed):
    • The Seed utilizes two rows of 20 pins. To ensure vertical clearance and allow for easy replacement, it should be seated in female pin headers rather than soldered directly to the main board.
    • Footprint: Connector_PinSocket_2.54mm:PinSocket_1x20_P2.54mm_Vertical (Assign two of these, spaced perfectly to match the Seed's width).
  • Top-Mounted I/O Jacks (1/4" Audio):
    • For the tight clearances of a top-mounted 125B, enclosed "Lumberg" style or low-profile PCB-mount jacks (commonly sourced from Tayda or similar suppliers) are heavily preferred over bulky, open-frame Switchcraft style jacks.
    • Footprint: Look for standard low-profile audio jacks in custom pedal libraries, or adapt a standard KiCad footprint like Connector_Audio:Jack_6.35mm_Neutrik_NMJ4HCD2_Horizontal depending on the exact physical part.
  • DC Power Jack:
    • Standard 2.1mm center-negative barrel jack.
    • Footprint: Connector_BarrelJack:BarrelJack_Horizontal.
  • Potentiometers (Mix, Threshold, Focus):
    • Alpha 16mm right-angle, PCB-mount potentiometers provide excellent mechanical stability to hold the board to the enclosure.
    • Footprint: Potentiometer_THT:Potentiometer_Alpha_RV16AF-4A_Vertical.
  • Analog Buffers (OPA2134):
    • Assuming a standard through-hole approach for the input and output unity-gain voltage-follower buffers.
    • Footprint: Package_DIP:DIP-8_W7.62mm (Use a high-quality IC socket; the PCB footprint remains the same).
  • Bypass Capacitors (0.1µF Film or Ceramic):
    • Utilizing single 0.1µF film or ceramic caps for the op-amp bypass rather than paired electrolytics saves valuable board real estate and simplifies the routing around the IC.
    • Footprint (Film): Capacitor_THT:C_Rect_L7.2mm_W3.5mm_P5.00mm (A standard 5mm pitch covers most WIMA or similar box caps).
    • Footprint (Ceramic): Capacitor_THT:C_Disc_D5.0mm_W2.5mm_P5.00mm.

Placement and Routing Strategies

When combining a powerful microcontroller like the Daisy Seed with analog audio circuitry, physical placement is your primary defense against a high noise floor. Digital clock signals and high-speed data lines emit high-frequency noise that can easily couple into sensitive analog traces.

1. The "Split Kingdom" Placement

Divide your 58mm x 72mm board into distinct analog and digital zones.

  • The Digital Zone: The Daisy Seed should dominate its own area, typically the upper or middle section of the board, keeping its high-speed digital lines (like I2S, SPI, or clock signals) localized.
  • The Analog Zone: Place the OPA2134 unity-gain voltage-follower buffers as far away from the Daisy Seed as possible—usually near the bottom edge of the board, closer to the footswitch. Do not intermingle the analog op-amps with the digital microcontroller pins.

2. Bypassing the OPA2134

The decision to use single 0.1µF film or ceramic bypass capacitors instead of bulkier paired electrolytics makes routing around the op-amp much cleaner, but placement is absolute key.

  • Location: Place the 0.1µF bypass capacitor physically as close to the power pins (Pin 8 for V+ and Pin 4 for V- / Ground) of the OPA2134 as humanly possible.
  • Routing: The trace from the power pin to the capacitor, and from the capacitor to the ground plane, must be as short and direct as possible. This creates a low-impedance path to ground, shunting high-frequency digital noise before it can enter the audio path.

3. Trace Routing Rules

  • Keep Analog Traces Short: Route your input and output audio traces (from the 1/4" jacks to the OPA2134 buffers, and from the buffers to the Daisy Seed's ADC/DAC) using the shortest, most direct paths possible.
  • Avoid Parallel Runs: Never route an analog audio trace parallel to a digital data line. If a digital clock line and an analog audio signal run side-by-side, the digital noise will capacitively couple into the audio signal, resulting in a high-pitched whine.
  • Cross at 90 Degrees: If an analog trace must cross paths with a digital trace, ensure they cross on opposite layers (e.g., analog on top, digital on bottom) at exactly a 90-degree right angle. This minimizes the cross-sectional area where interference can occur.

4. Copper Pours (Grounding)

  • Solid Ground Plane: Dedicate the entire bottom layer of your PCB to a solid Ground (GND) copper pour. A continuous, unbroken ground plane provides the lowest impedance return path for all signals and acts as a shield against electromagnetic interference (EMI).
  • Via Stitching: Use plenty of vias to connect any top-layer ground traces directly to the bottom ground plane.